-
- News
- Books
Featured Books
- pcb007 Magazine
Latest Issues
Current IssueThe Growing Industry
In this issue of PCB007 Magazine, we talk with leading economic experts, advocacy specialists in Washington, D.C., and PCB company leadership to get a well-rounded picture of what’s happening in the industry today. Don’t miss it.
The Sustainability Issue
Sustainability is one of the most widely used terms in business today, especially for electronics and manufacturing but what does it mean to you? We explore the environmental, business, and economic impacts.
The Fabricator’s Guide to IPC APEX EXPO
This issue previews many of the important events taking place at this year's show and highlights some changes and opportunities. So, buckle up. We are counting down to IPC APEX EXPO 2024.
- Articles
- Columns
Search Console
- Links
- Events
||| MENU - pcb007 Magazine
Estimated reading time: 8 minutes
Flex Time: Pointers for Your First Rigid-Flex Design
Material LayupIf you modeled the impedances as previously described, you are approximately 90% of the way towards a material layup. The report will give you the material cross-section with copper thicknesses, dielectric thicknesses, Dk values, etc. If you don’t have any impedance values to model, or you just need a straightforward material layup, ask your fabricator for their recommendations. Here is what they will want from you to get started:
• The overall number of layers in the rigid section(s): rigid sections can have differing amounts of layers of circuitry, but they should all end up the same thickness
• Desired copper thicknesses in the rigid section(s): innerlayers and outer layers with plating
• Number of layers in the flexible section(s)
• Desired copper thickness in flexible section(s)
• If there are more than three layers in the flex section, do you want them bonded together or loose-leaf?
• The desired overall thickness of the rigid board(s): over laminate, plating, or solder mask?
• Materials desired (FR-4, polyimide, etc.)
• Final finish
• Special requirements (UL, RoHS, REACH, lead-free and halogen-free assembly, etc.)
With this, your fabricator should be able to provide you with a suitable material layup as a starting point, which you can refine from there. Also, remember that many of the most popular laminates available on the market do not have a corresponding no-flow prepreg. Rigid-flex manufacturers have to use no-flow prepreg to keep the uncured resin from flowing onto the flexible areas of the board during lamination.
Your fabricator can recommend laminates with corresponding no-flow prepregs that will meet your requirements. Another good starting point for material layups is our Valu Build brochure[1]. Valu Builds offer simple, stable, and robust material layups for rigid-flex that are also very economical.
They are ideal for someone who is just starting rigid-flex, looking for a good entry point, and seeking the lowest cost in a rigid-flex design.
Detailed Print
Board designers and their fabricators often see the print as a list of requirements, which it surely is. But much more than that, the print communicates to the fabricator what your desires are as the designer. Without that communication, the fabricator isn’t always sure what you want. This is especially true for rigid-flex designs. Gerber files show your data and what you desire for holes, etc., but often it is not possible to tell where the rigid-to-flex transition areas are in the Gerber layers. This is where a detailed print—often much more so than an equivalent hardboard design—shows your fabricator precisely what you want.
Any dimensions across the flexible portions of the board should be referenced dimensions only. The flexible areas will expand and contract with temperature and humidity changes, so dimensions across the flexible portions of the board should be for reference only.
Rigid-to-Flex Transition Area
Design rules change around the flex-to-rigid transition area. There is a keep-out area on both sides of the rigid-to-flex transition line, particularly on the rigid side of that line. The keep-out area varies by the fabricator, but most fabricators will want you to keep all pads, traces, and vias a certain distance away from that line. In our case, we want all traces and the edge of pads at least 0.025” from the line and the edge of all drilled holes more than 0.050” from that line.
The reason is due mostly to cut-back coverlayer manufacturing (sometimes referred to as bikini processing). In high-reliability rigid-flex design and manufacturing, the coverlayer and bondply do not extend all the way through the rigid part of the board. They will typically extend 0.025” to 0.100” into the hard boards, but that also varies by the fabricator. The reason for using cut-back coverlayer is that the acrylic adhesive used to bond the coverlayer has a relatively high Z-axis coefficient of thermal expansion (CTE) rate—much higher than the surrounding laminates. During thermal cycling—think of RoHS and lead-free assembly temperatures—the expansion can put too much pressure on the vias and cause them to crack. Also, the acrylic adhesive does not drill, prep for plating, or plate well. Overall, it is not desirable in the rigid sections of your board.
There are times when it is not possible to use the cut-back coverlayer technique, and you must use full-sheet coverlayer/bondply.
However, whenever possible, use cut-back coverlayers and bondplys to provide the highest package reliability possible. Because of cut-back coverlayer, the edge at the flex-torigid transition area can have a slight radius to it. Any circuits or plated features in this area will struggle to image faithfully and will suffer yield loss.
For the same reason, the edge of the drilled via needs to be kept back from that transition line. If the vias are drilled partially through coverlayer and bondply and partially through prepreg, they will not yield—which typically shows as plating defects and opens at electrical test. It is the edge of the drilled hole that is critical and not the finished via size. If you call out a 0.012” finished hole on your design, fabricators usually drill that at 0.006” larger than the finished via size to accommodate plating thicknesses. If you put the edge of the finished via on the edge of the keep-out area, the drill itself will be drilling within the keep-out area.
It is wise to involve and consult your fabricator as to what their keep-out limitations are in the rigid-to-flex transition areas of the board, which can often vary by design. These are not absolute rules, just recommendations to get the best design with the highest yields and lowest overall cost possible.
Reference
1. Printed Circuits’ Valu Build Brochure.
Bob Burns is national sales and marketing manager for Printed Circuits Inc.
More Columns from Flex Time
Flex Time: Alternative Constructions in Rigid-flex DesignsWhy is Rigid-Flex So Expensive?