- design007 Magazine
Latest IssuesCurrent Issue
The Standards of Design
Our expert contributors discuss how PCB designers can utilize standards to save time and money, not to mention frustration. We also spotlight the newly updated version of the IPC Checklist, a handy guide that illustrates which standards cover which topics, from front-end design through assembly.
Rigid-flex: Designing in 3D
In this month’s issue, our expert contributors share their best tips, tricks and techniques for designing rigid-flex circuits. If you’re a rigid board designer considering moving into the 3D world of rigid-flex, this issue is just what the doctor ordered!
- Events||| MENU
- design007 Magazine
Designers Notebook: Flexible and Rigid-Flex Circuit Design Principles, Part 4March 30, 2016 | Vern Solberg, Consultant
Estimated reading time: 6 minutes
The most common rigid-flex circuit structure combines the attributes of the thin copper-clad base film and mechanical integrity of the glass-reinforced dielectric. While copper-clad polyimide film is the preferred material choice for the flexible portion of the circuit, the glass reinforced or rigid section(s) of the circuit may include an epoxy polymer or polyimide composition. The construction of the rigid portion of the rigid-flex circuit is very much the same as a standalone multilayer board.
All of the design rules for the glass reinforced-portion of the board (land pattern geometry for mounting surface mount devices, solder mask and the like) are now well-established. One unique facet of fabricating the rigid-flex product is how the flexible portion of the circuit is incorporated with the rigid portion of the circuit. As a general rule for multilayer PCB design, furnish a balanced structure by building up the circuit layers in pairs (4, 6, 8 and so on). Assuming that a single one- or two-metal flex will become an integral part of the rigid portion(s) of the unit, the designer must prepare for the integration of flexible and rigid materials. Ideally, the flexible section will be sandwiched in the center of the multi-layer structure. This allows the fabricator to complete all via forming and plating processes while in a panel format.
Because the flexible dielectric materials are significantly more costly than glass-reinforced organic dielectrics, some fabricators may recommend an alternative approach when integrating the flexible portion of the circuit with the glass-reinforced section. In this case, the flexible portion of the circuit will be designed to protrude a relatively short distance into the rigid structure. Drilled and plated vias are provided just inside the edge of the rigid section to complete the electrical interface between rigid-to-flex materials. Although the hole diameter and spacing is optional, the recommended edge-to-hole-center dimension for this process variation should be a minimum of 3.18 mm (0.125”) and the flexible film portion should extend into the rigid material by an equal amount.
To reduce mechanical stress and avoid damage to the narrow conductors on the flexible portion of the structure, a bead of flexible epoxy, acrylic or RTV silicone is commonly applied at the rigid-to-flex interface to extend the bending area away from the rigid board edge. The applied material forms a fillet profile and becomes a fillet-like strain relief in the rigid-to-flex transition zone. While the strain relief material will likely not flow beyond the upper surface of the rigid material, it may flow outward across the surface of the flexible dielectric from 1.0mm to 2.5 mm (~0.04” to ~0.10”).
Determining conductor density and the routing area requirement on the flexible portion of the circuit will depend on the number and width of signal conductors. For both single and two-metal flex the overall width of the base material must also provide adequate surface area for cover-layer film bonding. The general rule for conductor to dielectric edge is a minimum of 0.70 mm (~0.03”), but when possible, a wider area would be preferred.
Flexible circuit suppliers may publish their capability in two classifications, standard and advanced. While fabricators may specify 0.20 mm to 0.25 mm (~0.008” to ~0.010”) conductor lines and spaces for the 34-micron copper foil, 17-micron copper foil may enable a significantly narrower 0.07 mm to 0.13 mm (~0.003” to ~0.005”) conductor. Fabricators with more advanced imaging and pattern plating capability may be able to reduce geometries even further.
Conductor width and the spacing between conductors will be influenced by the copper foil thickness. As noted in Part 1 of this series, copper foils are commonly furnished in thicknesses of 17.0 microns (~0.0007") and 34.0 microns (~0.0014"). Foils as thin as 5.0 microns (~0.00018”) can also be furnished for very-high-density semi-additive circuit routing. Other issues influencing conductor width are current-carrying capacity requirement and spacing required for voltage isolation (refer to Circuit routing principles in Part 2 of this series).
Copper-plated vias are generally required on two metal-layer flexible circuits to provide the electrical continuity between sides. As previously noted, flexible circuit material can be furnished with the copper foil applied directly onto both sides of the base film or laminated onto the base film’s surface with a thin polymer adhesive. There are two basic via plating methodologies employed: button plate and panel plate. The button-plating process is commonly referred to as spot plating or pattern plating. The following is a somewhat simplified overview of via plating processes:
In preparation for button plating, a photosensitive resist coating is applied over the thin copper surface. Following imaging, only a small copper area around vias will remain exposed. The flex material is then subjected to an electroplating process that deposits copper at all exposed via sites. After plating is complete the resist coating is stripped from the base copper surface and made ready for a second coating of photoresist material. This resist material is then imaged and developed to define the final surface interconnect pattern. Only the circuit pattern and plated via sites remain once the chemical etching process removes the now exposed copper material.
This process can be employed for both adhesiveless and adhesive type copper clad films. There are two panel plate variations in use, selective plate and etch (semi-additive process) and full surface plate and etch (subtractive process):
- For the selective plate and etch, a photoresist coating is first applied over a thin copper foil or seed layer followed by an imaging process that exposes and defines the circuit pattern and via sites. A copper electroplating process is employed to build up only the exposed circuit pattern and complete the electrical interface at the via sites. The resist coating is finally removed and the remaining thin seed layer is chemically ablated from the base material’s surface.
- For full surface plate and etch processing, the copper-clad base material will be furnished with all via pre-punched, drilled or laser-ablated. Using the electroplating process, copper thickness is increased over the entire surface of the base composite material as well as completing side-to-side interface of all via features.
Fabrication methodologies have advanced a great deal. Many fabricators have implemented laser technology for just about every aspect of the manufacturing process. Direct laser imaging (DLI) has streamlined the pre-production process, eliminating film preparation, hard tooling for cover layer and final outline blanking, hole drilling and resist development for both subtractive and semi-additive circuit etching and plating processes. As an example, an established domestic flex-circuit fabricator with DLI process capability published the following:
- Conductor width and space
-Standard: 0.08 mm/0.08 mm (.003”/.003”)
-Advanced: 0.05 mm/0.05 mm (.002”/.002”)
- Minimum via diameter
There are a number of mechanical feature clearance guidelines for the flexible portion of the circuit. For example, the minimum distance between the exterior edge of the flex circuit and the edges of interior located holes and cutouts should not be less than 1.30 mm (~0.050”). A larger distance will likely make a more reliable part. Additionally, the recommended clearance between conductors and unsupported holes, pads or lands supporting hole features is 0.50 mm (~0.020”).
Capabilities and process methodology can vary significantly from one supplier to another, both domestic and offshore. Fabrication and material cost can vary as well. In selecting a source for flexible and rigid-flex circuits the designer must weigh these variables against any concerns affecting communication, logistics and any issue that may impact time-to-market goals. Detailed information for a wide range of dielectric materials are furnished in IPC-4101, Specification for Base Materials for Rigid and Multilayer Printed Boards.
Vern Solberg is an independent technical consultant based in Saratoga, California specializing in SMT and microelectronics design and manufacturing technology. To reach Solberg, click here.
AIM Solder, a leading global manufacturer of solder assembly materials for the electronics industry, is pleased to announce its new NC259FPA Ultrafine No Clean Solder Paste, which it revealed recently during the Productronica Germany trade show.
Real Time with... productronica 2023: Koh Young Discusses Semiconductor and Advanced Packaging Inspection11/27/2023 | Real Time with...productronica
Koh Young’s Harald Eppinger talks about the company’s technology for the semiconductor and advanced packaging market and how they address the challenges introduced by reflective components and micro solder deposits.
HyRel Technologies Attains ITAR Registration, Reinforcing Leadership in Robotic Solder Component Tinning11/27/2023 | HyRel
HyRel Technologies, a global provider of quick turn semiconductor modification solutions, announces the achievement of International Traffic in Arms Regulations (ITAR) registration.
Mek (Marantz Electronics), a leader in Automated Optical Inspection (AOI) solutions, used last weeks’ Productronica show in Munich to proudly introduce the SpectorBOX X series, a modular full 3D AOI system for THT solder joints and THT components.
Productronica 2023 played host to the IPC World Hand Soldering Competition, bringing talented regional solder champions from all over the globe to compete for the title of World Champion. Each competitor was given sixty minutes to assemble a complex printed circuit board with their performance judged in accordance with IPC-A-610 Class 3 criteria. Each competitor’s efforts were rated on the merits of the results achieved, scored on the quality of the assembly process, the electrical functionality of the assembly and the speed at which the assembly was produced.